Really Dumb Question

[krywarick6]

My brain is malfunctioning today.

I have brought 2 subassemblies together and want put an incontext relationship for some holes. The problem is that the subassemblies have their own incontext relationships for subcomponents and I can't modify them for the holes that I am trying to place in the upper assembly.

I thought of hole series, but this doesn't suit in this situation.

Any suggestions.

Christopher Zona - Product Designer
Loretto, Ontario

 

[CorBlimeyLimey]

It's not recommended practice but you select the Tools > Options > System Options > External References --- Allow multiple context for parts when editing in assembly

Or you could create a Top Level Layout Sketch and reference to that.

 

[sixftsix]

there is no such thing as a dumb question. besides there are a lot of people making money on "dumb" stuff. i wish i was one of them

 

[ShaggyPE]

No, here is a dumb question:

How can I save my model to an earlier version. I just upgraded my seat and no one else can view my files. I just converted the entire project to the new version... what should I do?

Now that is a dumb question. Please don't reply to this thinking it was serious.

-Dustin
Professional Engineer
Certified SolidWorks Professional
Certified COSMOSWorks Designer Specialist
Certified SolidWorks Advanced Sheet Metal Specialist

 

[fcsuper]

The only dumb question is the one you don't ask. Now, stupid questions, that's another story. However, your question is not stupid either. This is actually a good topic to cover.

Matt Lorono
CAD Engineer/ECN Analyst
Silicon Valley, CA
Lorono's SolidWorks Resources
Co-moderator of Solidworks Yahoo! Group
and Mechnical.Engineering Yahoo! Group

 

[krywarick6]

From sixftsix, "There is no such thing as a dumb question."

I knew I should have worded it differently. That's what the drill sargeants also used to say.

CBL, understanding that it is not recommended practice, what are the known problems that can occur? Does it give a rough time with rebuilding as if you were to layer equations? Did that once, boy was that a nightmare.

Christopher Zona - Product Designer
Loretto, Ontario

 

[drawoh]

krywarick6,

At the level of your top assembly, create a sketch within your sub-assembly.

Move to the sub-assembly and use the sketch to control your local feature.

When you finalize your drawings, remember to localize all of your parametric features. You can make an awful mess with parametric modeling, especially if you follow my advice, above.

JHG

 

[Theophilus]

Chris, I think the main risk in allowing multiple-context-edits like this is that you're much more likely to create circular references--which you don't want to happen. You may also have such circular references repeatedly changing something in an assembly and then changing something in the part, then assembly, then part, and accidentally create a singularity in space-time (or, in a best-case scenario see the blue screen of death or crash to desktop when opening the assembly).



Jeff Mowry

http://www.industrialdesignhaus.com

A people governed by fear cannot value freedom.

 

[krywarick6]

Jeff,

Thanks for the info. That's what I thought would happen. I did this scenerio with equations one time. That turned out to be a real mess.

Christopher Zona - Product Designer
Loretto, Ontario

 

[mjcole]

If you're using 2009 and the rest of your company is as well and can open your parts You might be able to do the Hole as An assembly cut Feature and select the option to "Propagate Feature to part level and do it that way. This will probably be the easiest way of preventing willy nilly In-Context relationships.

Prior to 2009 this kind of Assembly cut would only appear at assembly level and only the Hole Series you mentioned could be shown in parts at the Part Level.

If you've never used this option before its in the Group Box near the Feature Scope options.

Michael

 

[krywarick6]

Thanks for the food for thought.

Christopher Zona - Product Designer
Loretto, Ontario