Redefine orientation of the coordinate system

[elkhorn]

Hello:

Please advice.
I would like to redefine the orientation of the global coordinate system (XYZ) of the part assembly.

Thank you for your help.

Elkhorn.

 

[CorBlimeyLimey]

Is "the part assembly" a part or an assy? There are different methods for each.

If it's an assy, 'simply' adjust the mates to re-orient the parts, starting with the part at the top of the list. Hopefully the assy has been created with that first part being the only one referencing the main reference planes. If not be prepared to see and fix a lot of mate errors.


If it's a part you have several alternatives;

1) Use the Orientation tool (space bar).

To change the orientation of the standard model views in the Orientation dialog box:

In the Orientation dialog box, double-click one of the named views to select the new orientation. For example, if you want what is currently the Left view to become the front view, double-click Left.

Select the name of the standard view you want to assign to the current orientation of the model. For example, select Front if you want the current view to become the front.

Click Update Standard Views . This updates all of the standard views so they are relative to the selected view.

Click Yes to confirm the update.

This is probably the simplest method, but has the 'drawback' that anyone at any time can reset the CS to the default.

2) Use the Move?Copy Bodies tool to re-orient the part. This will create an extra feature in the Feature Manager which can also be reset by suppressing or deleting that feature.

3) Use the Reference Geometry > Cordinate System tool to create a new CS, Save as a parasolid using the Output coordinate system option, then open that parasolid. That will not create an extra feature ... in fact you will have no features at all unless you use the Feature Recognition function.