remembering chamfers?

[filbbb]

if i make a chamfer in a solid. remove all parameters of the solid as shown in pic#1

http://files.engineering.com/getfil...4004-a9be-824baf88cfe0&file=CHAMFER_EDGE1.JPG

i now try to replace (green) a face with the chamfer (red) it keeps the chamfer as shown in pic#2

http://files.engineering.com/getfil...4995-a21b-b1d02b33d6e0&file=CHAMFER_EDGE2.JPG

how & why is that possible?

 

[JohnRBaker]

Post the Part NOT the pictures.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[filbbb]

http://files.engineering.com/getfil...5-faae-4832-b9fd-d1c79605a2b8&file=model1.prt

IS THE MODEL

 

[Toost]

weird case. Call Gtac.


Regards,
Tomas

 

[JohnRBaker]

I've opened a PR and will report back what I learn.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[JohnRBaker]

OK, in this case, NX is actually working as designed.

The 'problem' is that the 'chamfer' face still thinks it's a chamfer despite the fact that all the features have been removed. You can verify this by using the Synchronous Modeling function, 'Label Chamfer', and it will indicate that the 'chamfer' face is already labeled as a 'Chamfer'. So since it thinks it's a 'Chamfer' it will always end up as a small chamfer face when you perform the 'Replace Face' function. Note that we are planning to add a function which will explicitly remove the 'Chamfer' label, but until then you have two choices: You need to either completely remove the 'Chamfer' lebel by exporting a Parasolid version of the model and reopening it as a new NX part file. At that point the 'Chamfer' label will have been removed and the 'Replace Face' function will now work as expected. The alternative is to not use 'Replace Face' at all, but rather use the 'Delete Face' function to remove the side faces.

Anyway, give it a shot as see if it works for you.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[filbbb]

Did you try to "delete face" on the solid? It don’t work & you get an error.
"delete failed because the remaining faces cannot close the area left after deleting the selected faces"
As simple as that solid was it should not have any trace of a chamfer? Other than the "parasolid" option this should not be happening.

 

[JohnRBaker]

Like I said, we're going to be implementing a function to remove the 'chamfer' label just that at the moment the system still thinks the face is a Chamfer.

As for the Delete Face issue, I forgot to mention that you need to use the 'Cap Face' option where you select the Chamfer as the 'Cap Face'.


John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[filbbb]

not sure what / where "cap face" is

 

[JohnRBaker]

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.