Result in different layers? 1

[seandree]

I use the command:
*SHELL SECTION, ELSET=ALL, COMPOSITE
0.012 ,3 ,MAT1 ,ORI_FRONT
0.016 ,3 ,MAT1 ,ORI_FRONT
0.200 ,3 ,MAT2 ,ORI_FRONT
0.016 ,3 ,MAT3 ,ORI_FRONT
0.200 ,3 ,MAT4 ,ORI_FRONT

How can I view the result for different layers in the Viewer, for instance the stresses? Do I have to specify integration points or something else? Do I have to specify on my output request that I want the results in different layers?

I hope someone can help me, I'm stuck!!

/Pablo

 

[corus]

Try looking under the field output requests option in Viewer, there might be an option under S (for stress).

 

[swallow]

Hi Pablo

What you need are the different section points of the cross section. In your SHELL SECTION definition you have chosen 3 integration points per layer. So you will find 15 section points for which you can plot the results in the ABAQUS/Viewer.
To identify the section points on which ABAQUS shall store the results, you need to list them in the *ELEMENT OUTPUT option.
If you use another postprocessor than ABAQUS/Viewer, things may be different. FEMAP for instance is not (yet) able to import results on more than two section points per shell element.

Hope this will help.

Rudolf

 

[seandree]

Thanks Rudolf!!

How do I specify the different shell section points on the *ELEMENT OUTPUT keyword?

When I look at the Result>filed output>Section points at the moment I only can choose between SNEG or SPOS, I want all the other section points as well!

I hope you can help me some more.

/Pablo

 

[swallow]

*ELEMENT OUTPUT
1,2,3,4,5,6,7,8,9,10,11,12,13,14,15
S,E

This will give the stresses and strains for the section points 1 to 15 (see ABAQUS Keywords Manual page 5.8-1). For the numbering of the section points refer to the ABAQUS/Standard User's Manual, Section 15.6.5.

This is how you can write it into the input file directly. I don't use ABAQUS/CAE.

 

[seandree]

Thanks swallow!!

This was a big help, now I know more exactly how I should do this!!

/Pablo