Sheetmetal from Solid

[RuudvdBrand]

Hello all,

I have a question. When working with NX Sheetmetal al use the feature "sheet metal from solid" a lot.
Now the question is when I use this feature en can make a sheetmetal part from a solid. but when I place the sheetmetal part in a assembly i Always see the solid.
This is also in drafting.
I don't want to have a seperate part for the solid.

How is het possible to hide te solid so it can't be see on de drawing?

Greats

Ruud

 

[JohnRBaker]

What version of NX are you running?

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[RuudvdBrand]

NX 7.5 and higher

I have found already a work around that's possible.
Whit a reference set i can control if i want to see solid or not i a drafting or assembly.

If you have better ideas the are always welcome.

 

[cowski]

Whit a reference set i can control if i want to see solid or not i a drafting or assembly.

That's a great way to do it, because that is what reference sets are for!

www.nxjournaling.com

 

[SvenBom]

I also use Layers. Particularly for drawings. If I use only reference sets, it will affect all the drawing views. The geometry will be hidden in all views are shown in all views. But if I use Layers, I can decide, in which view I don't want to show this geometry and in which I want. Maybe it is good to show this body in one view just for reference.
So, in your case, I would place sheet metal body on a Layer1 and solid body on a layer2.
When in drawing, I would select Layers Visible in View command. Then, I would select, which layers I want to show and which to hide in let's say top view and which in isometric view, etc.

 

[crecore]

SvenBom, AMEN! We also use master models so you can control the reference sets and layers seperately for the drawing compared to the assembly as well! I also merge gerber file "assembly data" for PCB's using a dxf import as lines and arcs and place it on the surface of the model. I tie these to both layers and reference sets. In said components master model drawing I can show one view with the gerber data, "roadmap" if you will, that corresponds to my gerber bom (imported to a table) and a second "mechanical" view with the gerber data shut off using layers visible in view. Without a second instance of the same component you cannot toggle two different reference sets so the layers are another tool in the tool box. People that want to throw out layers just arent using the software to the full potential.

NX 8.0.1.5