Sketching in drafting

[BrandM]

I am using NX7.5. I have view that I only need to use part of on a drawing. I can use view boundry to shrink the view to show what I want, but I need to sketch a couple of arcs in to indicate rotation of the parts, of the assembly, in the view. The sketched line needs to be symetrical, when it is one end will be out of the edge of the new boundry. Is there a way to create a boundry to show what I want to see of the assembly in the drawing and still be able to sketch whatever size I want to? In Ideas you could create a user defined boundry to limit what was shown from the model or assembly, and then be able to draw anywhere around it. Is there anything similar to this that can be done?

 

[ingallspw]

Can you create a sketch in modeling and use it to show up in your views?

If you do not want the sketch in all your views, move it to a layer that you have nothing else on that you need for drafting and then select Format > Layer Visible in View. Then select the views you don't want the sketch in and select that layer as invisible.

You may also need to add the sketch to your "Reference Set" (Format > Reference Sets...)

 

[JohnRBaker]

Why not just sketch on the Drawing?

You can sketch either on the face of the Drawing itself or within any one of the views. And if you do sketch inside a view, the sketch will move with the view and if the sketch curves extend past the original view boundaries, when the view is updated the boundaries will automatically update so that those curves are visible in the view.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[BrandM]

I do want to sketch on the drawing and in the view so that the sketch will move with the view. I will try to explain better what I want to do. I am working on a multi page drawing of an assembly with many options. Their are arrangements for all of the options. One of the options is a small piece of the large assembly, and it has its own arrangemant. I want to create a view similar to a detail view that shows the option and the background of the rest of the assembly directly behind it. I then want to sketch an arc to show rotation of this option, but to give the arc any length it will be outside of the boundry created around the option. If I open the view to show the sketch I want then I show more of the assembly than I would like. I would like to be able to create a boundry size for the view of the opotion and a boundry size for what I want to sketch. I do not want to sketch in the main view and have the sketch not associated to the arrangement view.

 

[JohnRBaker]

Sorry, if you want the Sketch curves to move with the view you will need to sketch them inside the view and therefore they will become part of the view which means in order to see them the boundaries will have to extend sufficiently to show the sketch curves. You can always place the sketch on the face of the Drawing itself (not in any one view), but you will then have to move the sketch manually if the view is moved.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[BrandM]

I was afraid of that, but was hoping it wasn't so. Do you know if that is an enhancment that is being looked at? I was an Ideas user and this was easy to do in its drafting.
Thanks for your help.

 

[JohnRBaker]

Now there are ways to hide extraneous content from a view, but it has nothing to do with sketched curves and boundaries, but rather editing the appearance (in this case whether something is visible in the view by perfroming view dependent edits or by indicating whether certain components are visible in which views. But there is no automatic, make the view boundaries larger without changing what is seen in the view.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.