Text on a beveled, curved surface (cone). 1

[Legrand]

Can text be "wrapped" to a cone? I would like the text to be engraved to athe same depth on this surface and I have tried several iterations of planes, sketches, etc. however I have yet to find anything that works. Has anyone been able to do this?

Thanks,

Legrand

 

[SBaugh]

See Wrap feature in the help

Regards,

Scott Baugh, CSWP
3DVision Technologies

http://www.3dvisiontech.com

http://www.scottjbaugh.com

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faq559-716 - SW Fora Users

 

[Legrand]

I did. That's why I'm here, it didn't help. I know enough to look in the help file...

 

[rockguy]

Did you try a cut exrude with the "offset from surface option? There is also a technique to do this using a sheetmetal part.

 

[rporter]

Yes in 2004 and 2005 it can be. The scketch plane has to be tangent to the surface you want to wrap around. After you have finished the sketch just cloase it. In the Feture manager tree clisk on the sketch then click on insert, fetures. Select the wrap feture. Select the settings you want and how deep or high to make it then click on the ok check mark.

 

[Legrand]

I'll try that tomorrow when I get to work. I think the problem might have been that I sketched the text on a circle first, thinking I could drop it down onto the cone. I then created an angled plane tangent to the cone, but the text was still on the circle and I got an error trying to rebuild. I'll try a straignt line on the tangent plane tomorrow.

Thanks.

 

[CorBlimeyLimey]

The line or arc which you want the text to follow must be from a seperate sketch.

Create the cone.
Create a tangent plane.
On the tangent plane, create a sketch showing the line or curve you want the text to follow.
Close the sketch.

Create a new sketch & use the sketch text tool to create your text, selecting the previous sketch as the path.
Close the sketch.

Activate the Wrap tool, select the text sketch, whatever options you need, the cone surface & then finish.

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[ejc]

Does the line or arc have to been in a different sketch? I've added text to parts before, though never using the wrap function, where the line/arc was part of the same sketch as the text. However, when doing it this way, the line/arc must be a construction line.

 

[CorBlimeyLimey]

ejc ... My apologies ... the line or arc does not have to be in a different sketch. I'm just so used to creating seperate sketches for things. I stand corrected ... thanks for the reminder.


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[Legrand]

OK... Thanks for all the input, I did get it to work, for the most part... One thing though, can anyone tell me if there's an easy way to make the text straight on the cone, with reference to the bottom surface? i.e. as in along the red line in this pic.

 

[CorBlimeyLimey]

You will have to use an arc (with the centre nearer the small er cone dia) as the path & adjust the radius to suit.


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[Legrand]

Well... It's taking a bit of "tweaking" but I am getting it to work. I'm trying to wrap a long line of characters around a short surface. I kept getting errors, so I thought I'd break up the wording and apply it in several places around the angled surface. I managed to get the first part applied, but the second portion, which is shorter than the first (on a new plane, but using the same arc parameters (radius, positioning, etc.)) will not work. I keep getting the following message:

"Wrap only allows one or more closed countours that are disjoint in a sketch"

What the heck does that mean? Solidworks sure likes to use "disjoint" in all their messages.... Can someone elucidate me on the meaning of this?

Thanks.

 

[SBaugh]

When you are in the sketch try going to Tools\Sketch tools\Check sketch for feature. Pick the feature you want to use in the drop down and click Check. Hopefully it will tell you if and where the problem is. The problem is probably in the sketch.

Regards,

Scott Baugh, CSWP
3DVision Technologies

http://www.3dvisiontech.com

http://www.scottjbaugh.com

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faq559-716 - SW Fora Users