Toggling Exploded State in Drafting View 3

[Recon1775]

Can someone please enlighten me on how you toggle an exploded state of the model in a drafting view?
I have the exploded state created in the master assembly model and all the views are created based on the master model, but I can't figure out how I toggle the exploded state in one particular view.
I've seen other posts that say to toggle it but no details on how (menu picks). Also I've seen posts that say you can also create a view for the particular exploded state but the details on how that works is also a bit lacking.
Using NX 9

Thank you so much!

 

[JohnRBaker]

Exploded views must be created in the Drawing part file itself. They cannot be inherited from the Master Assembly.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[Recon1775]

Oh ok. Do I make the master assembly the work part and create the exploded state while in the context of the drawing specification?
After I create the Exploded state how do I set a view to use it?

Also I read this in the help file which really confuses me. Could you please help me understand this statement?
I thought this meant I needed to create the exploded state in the master assembly model but I guess I'm not understanding this statement.
"Unlike other views, you can not display an exploded view from a master model in a non-master part. If you are using the master model method to create non-master drawings, you must create the exploded view in the Modeling application of the non-master drawing part."

Thank you for the help.

 

[JohnRBaker]

No, while still in the Drawing part file, change your application to Modeling and then create your exploded view. Then when you return to the Drafting application, simply add the Exploded View, selected from the Drawing Part file when asked to add a new Base View to the Drawing. If while you were in Modeling, you left the Exploded View with the explosion active, it should be in that state when you add it to the Drawing.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[Recon1775]

So after I create the exploded state in the Exploded Views menu area where do I find the selection in the Base view to change it to that state?

Or is it only available when you're creating the view the first time?

Thanks!

 

[SDETERS]

Reconbomber. Have you looked into doing these "exploded Views" as an arrangement in your master assembly? I have found it is so much easier to have a different arrangement with constraints toggled off. Exploded Views do not work nicely for us at all. The tracelines do not work but I use a special part that contains the curves as tracelines.

 

[cowski]

Also I've seen posts that say you can also create a view for the particular exploded state but the details on how that works is also a bit lacking.

For this post, I'm going to assume that we are using the master model method (the assembly has been added as a component of the drawing file). The drawing file should be the display and work part.

While working with exploded views, I suggest turning on the model view names option (Preferences -> visualization -> names/borders -> show model view names). The name of the current view will now show up in the lower left corner of the view window, something like: "Top WORK". If you use multiple view ports, the view name will show up in the bottom left corner of each. When you apply an explosion (exploded views -> choose explosion from drop down) the view text will change to something like: "Top WORK (EXPLODED)". Switch to the drafting application and start the 'base view' command; make sure the "part" chosen is the drawing part file and not the model part file, choose the view that has been exploded (in our case the Top view) and place it on the drawing. The drafting view will show the exploded top view. You cannot toggle the explosion status on the drafting view; a drafting view that was added when the model view was exploded will always show the explosion (and vice versa). You can switch back to modeling, un-explode the view, switch back to drafting and add the view again for exploded/unexploded views.

Personally, I like to create a view for exclusive use with the explosion, but this is not required. My exploded views are generally based on the trimetric view; in the modeling application switch to the trimetric view (right click in the graphics window background -> replace view -> trimetric). Now save a copy of that view: menu -> view -> operation -> save as... Give it a name that makes sense to you, something that you will later recognize as an exploded view. Create and/or apply the explosion to your new view. When you place the exploded view on the drawing, the name that you gave your new view will show up in the list of view options. Another benefit of a custom view for the explosion is that you can tweak the view angle to get better visibility into your assembly without affecting any other view.

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[Recon1775]

SDETERS thank you for the great suggestion that actually works out nicely for some of the exploded views I need to do. Much easier to work with.

cowski Thank you so much for the detail description on how to make this all work. I have it working now and on the drawing. Thanks so much!