Weldment Cut list for selected bodies

[pllmoreau]

Hello,

I do large weldment parts with multiple weldment cuts and I have a cut list at the beginning with all the bodies, then I do the drafting for individual parts in later pages, would it be possible to insert a cut list for a view on the current page that will only have the bodies that are in that view that I chose with ''select bodies'' inside? I tried selecting the view before asking a cut list but it kept bringing the whole cut list.

thank you!

 

[SBaugh]

That is correct a weldment is a bunch of bodies, but a weldment cutlist does not work the same as a BOM. When dealing with a BOM you can suppress parts in the assembly and the BOM excludes them.

In a weldment cutlist, you cannot suppress the bodies. Does not matter if you are using multiple configurations. I thought the same thing at the beginning of this thread, but later I got to thinking about it and I tested it out. There is no option to suppress the body. I can suppress all the bodies, but not specific bodies.

There is an option to "Exclude bodies from a Cutlist", but that's a global option, not a configuration option. which means you will see that every configuration.

If you know of a way please enlighten us because I have not seen that solution.

Attached is an example file I made in SW 2023.

Scott Baugh, CSWP
Mechanical Engineer
Ciholas

https://www.ciholas.com/

"If it's not broke, Don't fix it!"

faq731-376

 

[SBaugh]

I should also mention that you can hide a body, but again that does not change the cutlist items. It does hide the body in the drawing and it's global for all configurations, not config-specific.

Scott Baugh, CSWP
Mechanical Engineer
Ciholas

https://www.ciholas.com/

"If it's not broke, Don't fix it!"

faq731-376

 

[jassco]

Hi, SBaugh:

You don't hide anything. You just need to delete bodies.

Best regards,

Alex

 

[Jboggs]

"There is no option to suppress the body."
This is true. You cannot suppress bodies. You can only suppress features.

But there is a feature that allows you to Delete Bodies. So ... you add that feature to "Delete Selected Bodies" in your feature tree. Then you can retain or suppress that feature as required in each configuration.

Just be careful with Child/Parent relationships! You do not want to delete a body that is required by a subsequent feature in the feature tree. Any "Delete Body" features must be at the END of the feature tree.

 

[SBaugh]

That's true that would work. I did not think about that. However, like you mentioned if you have any features on the bodies that could get sketchy pretty quickly.

Scott Baugh, CSWP
Mechanical Engineer
Ciholas

https://www.ciholas.com/

"If it's not broke, Don't fix it!"

faq731-376

 

[Jboggs]

I think the OP was asking for individual bodies to have the same cut list item number in each different configuration. This "delete body and suppress approach" will probably disrupt item number assignments in various configurations, but other than that it should work for him.

 

[SBaugh]

That is true, which is another reason why I place a table outside the sheet and hide it then just use balloons to specify which items you are looking at. They can always refer back to the sheet 1.

Scott Baugh, CSWP
Mechanical Engineer
Ciholas

https://www.ciholas.com/

"If it's not broke, Don't fix it!"

faq731-376

 

[jassco]

Hi,

Solidwork is designed to support 7 international standards. I think the OP is trying to create his own standards.

Best regards,

Alex

 

[pllmoreau]

Hello all

Sorry I was not working for the holidays
Thank you again for the thread, I see it is not an easy problem, from what I understand the solution would be to insert features to delete bodies and supress those in different configurations and use those configurations in the different cutlist.
SBaugh: for the cutlist outside the page, what I needed is the cutlist itself shortened to the selected bodies, the baloons work fine even if the cutlist is not on the page I am working on with the selected bodies.

 

[SBaugh]

I understand what you asked for, I was giving you an alternative that I have used over the years that worked fine for me.

Scott Baugh, CSWP
Mechanical Engineer
Ciholas

https://www.ciholas.com/

"If it's not broke, Don't fix it!"

faq731-376