Add exploded view to Model view 3

[pratyu]

Hi there!

I have created an exploded view along with the tracelines in my Modeling (Assemblies) environment. I have added the view containing all the parts along with the tracelines by View->Add View and I'm able to see the name of it in Information->Other->View. I saved the part.

I use another UG file only for drafting purpose (and it is linked to my Assembly part)
However, when I want to put the Exploded view on my drafting file, I am unable to do so. In the Base View->Model View-> Model View to Use, I cannot see my Exploded view.

Please help!

Thanks in advamce!!

 

[cowski]

Exploded views must be created in the drawing file. You cannot create it in the master file then use it in the drawing file. This may change in future versions of NX, but it is a current limitation.

www.nxjournaling.com

 

[SDETERS]

I have used Arrangements for my exploded views instead of using the Exploded view in my drawing. One issue with doing this way is that the tracelines function can not be used.

 

[pratyu]

How to create exploded views in the drafting file?

 

[JohnRBaker]

While in a Drawing file you can still change to the Modeling application. Of course, the Drawing will be removed from the display but it will reappear when you return to the Drafting application after creating your exploded view(s).

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[pratyu]

Thanks John! You hit the nail. Thanks a lot!

 

[NutAce]

Hi John.

Any plans from Siemens to change this is in the future? Will it be possible, working master model, to create your eploded views in your model?

Is there some special reason behind this way of working as it sits now?

Ronald van den Broek
Mechanical Engineer
Cad Environment Coordinator
Wärtsilä, Propulsion Services
NX8.5.2 / TC9.1.2
HPZ420 Intel(R) Xeon(R) CPU E5-1620 0 @ 3.60GHz, 32 Gb Win7 64B
Nvidea Quadro4000 2048MB DDR5

 

[pratyu]

John, Just found a LIMITATION!

Your option works great, except that I cannot use it on Waved Bodies!

Please suggest!

 

[SvenBom]

@pratyu
By Waved Bodis I guess, that you mean models, created with Wave Geometry Linker. Right? So, what is the probem with those bodies and Exploded View in draft file? What cann't be done?
What John has described is the proper way of doing this. And in step-by-step it works like this:
1. create a drawing
2. switch the application to Modeling. Now, you will see the assembly. If you check the Assembly NAvigator, you will see, that top assembly is the drawing and that the first sub-assembly is your assembly
3. now, create the explosion and then click on Auto-Explode components. Some components will be moved to the new position and some not. If I remember correctly, NX will move to the new postion only the components, that were constrainted with Touc and Aligh constraints.
4. Becaus of what I have described in step 3, wave bodies will not be moved. For those components, use Edit Explosion and then Move Object command. And move the component to the desired location.
5. When you will define your explosion, save the view as MyExplosion or whatever you like.
6. now switch from Modeling back to Drafting.
7. When you will place another view on the drawing, you will have an option to select previously saved model view, MyExplosion.

I have just tested this, and it works.

 

[JohnRBaker]

I have to admit that for years I also felt that you should be able to create an exploded view in an Assembly model and then using the Master Model approach to create a Drawing that this exploded view should then be available to add to the Drawing.

However, recently I've been having second thoughts. The reason is that an exploded view is something that is used to 'document' an Assembly, like what a Drawing is used for, and if you accept this idea that with the Master Model approach, the 'documentation' is separate from the Assembly model itself, then it makes sense that the Exploded Views should also be considered as part of that 'documentation' set, which is found in the Master Model Drawing. Besides, things like 'trace lines' are not all tht different than centerline marks and you wouldn't want centerline symbols all over your model, now would you? So why would you be willing to include 'Trace Lines' in your MODEL when they only serve a purpose as part of an image on the exploded view, something that would be found on one of the sheets of the Assembly Drawing, along with a Parts List, Section Views, Annotations, Dimensions, etc.

Anyway, that's my humble opinion, for what it's worth.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[pratyu]

SvenBom,
I've been doing exactly the same that you've described. What I observed is, this doesn't work with the waved body. When I was trying to do the part you've described in Step 4, I couldn't select the linked body as such. Even "Select from List" doesn't show the waved body. When I put my cursor near that area, other parts are highlighting along with the waved body. But, the waved body alone doesn't highlight or select.

FYI: Waved body - Insert> Associative copy> Wave Geometry Linker> Body.

 

[cowski]

Has the body been wave linked into the assembly file, or is it in a separate file and added to the assembly as a component?

www.nxjournaling.com

 

[pratyu]

The body has been wave linked in the assembly file.

 

[SvenBom]

OK, this is why you can not explode this body. It is the body in the assembly file level. But the explosions works only with components. When you are in edit explosion command, you can see, that Type Filter has only Component option. So again, you can explode only components.
If your body was copied to the new file or better said, to the new component, then you wouold be able to explode it.
You can move such body with Edit/MoveObject command, but the work part has to be your assembly, where this body resides.

 

[pratyu]

SvenBom,
Yeah! It works fine with linked bodies in other components.

Is this a limitation?

 

[cowski]

Is this a limitation?

That's like asking: "Why can't I use a hammer to strip these wires?"
Every tool has its limits. In this case you were asking it to do something it was not designed to do.

www.nxjournaling.com

 

[SvenBom]

I wouldn't say, that this is the limitation. This is how it must work. It is the same as with parts list. You will get listed only the components and not the solid bodies, that are in the top assembly level.
You have to understand, that wave body, that you have created, is nothing but a solid body. It is the same as, if you create a body with extrude command. It is just a solid body. If you want to create an explosion, you must have a separate component. As already said, explosion will work only with components.
So, for you to solve this problem, you have to create new component within assembly, make this component work part and create a wave body in this part. Then, you will be able to explode this component, too.

 

[jasonJJ]

TIP:
I have found that you can extract curves from the edges of the body you are trying to wave in the explosion and then move the waved body (because it wont wave in its exploded position) to the curves created. Just use the 3 point CSYS to CSYS ( I like "origin, x-point, y-point).
If you need a copy of a solid in the waved position in the assembly.