Broken Dimensions on Detail Views

[biggles2]

Using Version 12

I am creating a drawing of a 400mm diameter part and need to show small features on the diameter.

I have created the drawing at 1:1 then added a detail view at 5: to show the features in question.

The problem is I need to dimension the feature as a diameter in the 5:1 view. I can not see a way of doing this which does not require a centreline way off my drawing sheet.

Can anyone help please?

 

[DNA]

Biggles2,

I would recommend going into the draw in view command and adding the centerlines there. This will allow you to dimension to it later in your detail veiw.

DNA

 

[biggles2]

Perhaps I did not make myself clear.

The issue is not the absence of a centreline, but the fact that in a 5:1 detail view a centreline if used, would be some 600mm or so over the edge of the drawing sheet

I need some way of creating a dimension driven by the part, with a single leader line and a short dimension line on which the dimension sits.

I understand that to give the impression of this I could dimesion not to the centreline but to some other nearer point, blank the leader line and dimension text then use the prefix facility to type in the value I want displayed.
This however is dangerous as the value would not alter should any change be made to the part.

Is there some other option?

 

[testy]

I don't know if this will work in SE but in Solidworks you can create a break line (like you would use to dimension long parts)to move the centerline closer to the feature you are dimensioning.

 

[tewers]

I'm not sure if you can edit an existing dimension to do this - but I have a custom dimension style which creates dimensions with horizontal embedded text which I use for all diameter and radial dimensions. This doesn't give the big dimension you mention, just a small 'leader-like' dimension when you move the text outside of the diameter. Settings for this are Text = Horizontal, Embedded. Lines and Co-ordinates = Connect Un-checked, Project Centrelines Unchecked.

When I try to modify properties of an existing dimension to that above, it doesn't seem to work. But creating a new style as above does, especially when you move the text outside of the diameter being dimensioned

Hope this helps....

 

[Pekelder]

It's a bummer I'm not at a SE-console right now, but you can dimension a diameter with a broken dimention. It's an option in the Smart-dimension toolbar (the yellow dimension-thingy). It let's you place the dimension and select the break-off-point of the arrow. Try arrond, you'll bound to find it somewhere. I'm not absolutely sure it 'll work in a deatail view though..

Regards,

Pekelder

 

[jdrawlinson]

Try this:

1) Re-position the detail view off the page. I do this so I can see clearly.

2) On your 1:1 view, re-size the circle so it catches the center of the 400mm diameter. This will also re-crop the detail view.

3) Place the dimension on the detail view using. Since the view is re-cropped, you should see the center in the detail view.

4) On the 1:1 view, re-crop the view to the original view, then re-position the dimension.

5) Reposition the view on the drawing.

If you would like to see a detailed presentation on this effort, let me know.