CONSTRAIN A LINE TO POINT IN SKETCHER?? 1

[kadego]

Hi All
I am trying to constrain a line to a point in sketcher with no success.
I can pick the line but it will not let me select the point.
Can someone please explain how to do it.
Dave

 

[JohnRBaker]

What version of NX are you using? I have no problems whatsoever constraining a line to a point in NX 4.


John R. Baker, P.E.
Product 'Evangelist'
NX Product Line
UGS Corp
Cypress, CA

http://www.ugs.com

http://www.plmworld.org/museum/

 

[kadego]

Hi John
I am using NX3 (customer requirement)
The point I am using is an intersection between a datum plane and curve. I have also tried projecting the point into the sketch to no avail.
Dave

 

[JohnRBaker]

Using NX 3.0.5.3 I created a Datum Plane, passed a Line through it and then created a Point at the interestion of the Datum and the Line. I then created a Sketch, created a Line and then constrained the Line to the Point. Note that the Point was not even on the same plane as the Sketch. Also note that I tried with with both a 'Smart' Point (Associative) and 'Dumb' Point (non-Associative), and it worked both times.

Now there is ONE special requirement IF you are creating 'Smart' (Associative) Points, and that is that since 'Smart' Points are actually 'Features', and therefore are 'timestamped', they must have been created BEFORE the Sketch. If they are created AFTER the Sketch, you will not even be able to select the point, let alone use it to constrain an object.


John R. Baker, P.E.
Product 'Evangelist'
NX Product Line
UGS Corp
Cypress, CA

http://www.ugs.com

http://www.plmworld.org/museum/

 

[kadego]

Thanks John
That was it.
Being a full time Catia V5 user and part time NX, I keep forgeting that the order ALL things are created in NX matters.
Have a star.
Dave