Embedded Sketch Question

[rmorgan890]

Just moved to NX 1953 from NX 12.

Previously, I was able to right mouse click on features with embedded sketches and pick Edit Parameters and the sketch dimensions would appear without going into the sketch.

I no longer see this in NX 1953. Is this functionality gone?

Thank you,

 

[jerry1423]

That happened to me too and I was able to resolve the problem.
I will get back to you when I figure out what I did,
What type of feature is attached to the sketch ?

Jerry J.
UGV5-NX1961

 

[jerry1423]

Can you show a screenshot of your model tree ?

Jerry J.
UGV5-NX1961

 

[rmorgan890]

It's not dependent on other features. For example, the problem is the same for a model that contains just one extrusion, as well as a model with fifty features.

 

[cowski]

Are you working with a file from a previous version of NX (one that used the old sketcher), or are you working with the new sketcher?

www.nxjournaling.com

 

[rmorgan890]

Both. In the old file, i noticed the existing features with internal/embedded sketches this still works, but if i create new feature it doesn't.

As a side note, I think "internal sketch" is probably the correct term. Not "imbedded sketch." My bad.

 

[cowski]

In that case, this is probably related to the new sketcher. In the old sketcher, an expression was created for every driving dimension that you added to the sketch. In the new sketcher, this is no longer the case; an expression is only created if you explicitly tell NX to create one. I suspect that NX is only going to show the dimensions that have expressions associated to them when you use "edit parameters".

www.nxjournaling.com

 

[rmorgan890]

Yep, that's it.

Using Rapid Dimension, I just created a sketch dimension and under "Driving" i checked "Expression", and it worked.

Thanks,

Is there any down side to making Sketch Dimensions Expressions, other that maybe a few extra clicks?

 

[cowski]

Based on Pat's answer in this thread, I guess eliminating expressions was done (partly, at least) for performance reasons.

www.nxjournaling.com

 

[rmorgan890]

Thanks for your help!!