Lightweight representation drawing with hidden lines

[Mukundh]

I am trying to place a drawing for Lightweight representation assembly. Unable to get the hidden lines options in Lightweight mode. Is there any setting in drafting to get hidden lines for lightweight assembly.

NX 9.0.3.4 MP2

Thanks in advance
Mukundh

 

[JohnRBaker]

You have to make sure that the views on your Drawing are what's called 'Smart Lightweight' views. A simple 'Lightweight' view is an older style of lightweight view and does not provide any hidden line options. It's only shown with hidden line removed, period.

Now you can't change a 'Lightweight' view into a 'Smart Lightweight'. You have to create a view as a 'Smart Lightweight' to start with. Now you CAN switch between 'Exact' and 'Smart Lightweight' but only if if the views were added to a Drawing in NX 8.5 or newer version of NX. To see what the view type is just place the cursor over the boundary of the view and and when it highlights you'll see the type and name of the Drawing view.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.

 

[Mukundh]

Hi John,

"Smart Lightweight" views are not able to show the lightweight represented bodies. Only Exact bodies are shown when placed with "Smart Lightweight".

I want to create the drawing with lightweight weight represented data and not with Exact. Since, Exact representation will take more time to load and update the view.

Regrads,
Mukundh

 

[JohnRBaker]

Your part files have to have lightweight representations in them to create Drawing using the Smart Lightweight views, You night have some older parts, like hardware and such, which has not been updated to at least NX 7.5 level. It's best to run Part refile using the option to create new lightweight represetations.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Digital Factory
Cypress, CA
Siemens PLM:
UG/NX Museum:

To an Engineer, the glass is twice as big as it needs to be.