Section View Letter already in use 4

[cowski]

We recently recieved a drawing file with 2 section views on it (A and B). When you update the drawing views, section A-A is really section C-C; someone fudged the view name by typing in the A-A. When you try to correct the problem by editing the view label a message box pops up that says letter A is already in use. There are only 2 secion views, no other special views (detail, broken, etc).

This is on NX2. Part cleanup does not help. Any ideas what is causing it and how to fix it? It is as if there were 3 section views to start, then deleted section A and now the letter A is not available.

 

[ewh]

Are there any additional "scratch" sheets that A-A could be on? Is it somewhere out in space beyond the drawing boundary?

 

[cowski]

Nope, no other sheets, and the only other views are 2 or 3 of the canned orthographic views.

 

[ewh]

Graspimg at straws here... Does it show up in the part navigator?

 

[cowski]

Only the canned views and the 2 section views show up in the list.

One more thing I found out: the people we got the file from use a document management system (I don't know which one) while we do not. Is it possible that their document manager marked section A as being used (on a previous revision) and now will not let us use it? Now I'm grasping at straws since I know almost nothing about document management systems.

 

[jackley]

Wonder if it's being referenced in a spreadsheet, or something internal to the part file?

Justin Ackley
Designer
jackley@gmail.com

 

[jackley]

Wonder if it's being referenced in a spreadsheet, or something internal to the part file? Or Expression?

Could you reference a view to these? I am not sure.

Justin Ackley
Designer
jackley@gmail.com

 

[toniechang]

In a couple of years, the UG code will become so weird that only the old "procedural" generation will understand it ...
A pity when compared with what's done on half the price programs. Really.

 

[JohnRBaker]

"In a couple of years, the UG code will become so weird that only the old "procedural" generation will understand it ..."

Could you please explain exactly what you mean by this comment?


John R. Baker, P.E.
Product 'Evangelist'
NX Product Line
UGS Corp
Cypress, CA

http://www.ugs.com

http://www.plmworld.org/museum/

 

[Xwheelguy]

cowski,

You may have already tried this, but based on the posts above, I didn't see anything mentioned about it.

I believe that all views have a letter associated to them, not just section, detail or broken views. Therefore, it could be any view on the drawing that is using the letter A. Right click on every View Label then click Edit View Label from the pulldown. When the View Label dialog comes up, click on View Letter and look at the bottom of the dialog. Make whatever changes you need to make.

HTH,

Tim Flater
Senior Designer
Enkei America, Inc.

http://www.enkei.com

Some people are like slinkies....they don't really have a purpose, but they still bring a smile to your face when you push them down the stairs.

 

[toniechang]

John,

I meant that after 6 years on UG and having felt the big NX migration and promises, I'm very upset now by what I saw last week : a German CAD parametric system built on a brand new core and able to handle the full picture of hundreds of thousands of parts on an office PC + having all the "Windows based" powerful and eqsy-to-use drafting possibilities of an AutoCAD last generation and as straight to program and understand as the real VB.NET (no wrapping here) ...
It was a good idea to update UG instead of rebuilding the core from scratch but it's getting really late now and NX still behaves like a dinosaure written on the old C for most of its functions.
Not more, not less.

;-)

 

[JohnRBaker]

Have you seen NX 5 yet?


John R. Baker, P.E.
Product 'Evangelist'
NX Product Line
UGS Corp
Cypress, CA

http://www.ugs.com

http://www.plmworld.org/museum/

 

[toniechang]

Yes, I did.
Unfortunately, my company likes to skip the uneven
releases and go for the next even upgrade only when the next uneven is out; not to have to face the numerous bugs, they say ...

 

[JohnRBaker]

Well then you're going to LOVE NX 6 ;-)


John R. Baker, P.E.
Product 'Evangelist'
NX Product Line
UGS Corp
Cypress, CA

http://www.ugs.com

http://www.plmworld.org/museum/

 

[toniechang]

Yep ! ;-)

 

[cowski]

Thanks Tim, that was the problem. Someone had switched 'view name' to 'view letter' on one of the ortho views which then took over letter A. It was not obvious since view labels were not displayed for the ortho views.

ewh and jackley, thanks for the useful suggestions.

 

[jackley]

I am not so sure mine was very useful. Not certain you can even tie a view to an expression/spreadsheet at all.

But thank you though. =)

Justin Ackley
Designer
jackley@gmail.com

 

[Xwheelguy]

No problem, cowski. I'm glad that turned out to be the issue and not something really obscure.

Just to follow up on this a little bit:

As I made the above post based on past experiences, I decided it might be wise to confirm everything before hitting the post button, so I started NX and made a simple block-based part with a Slot in one face. I then placed a Top view on a drawing to watch the behavior of NX. What happens is that when you place a view, it begins with letter A, regardless of the view type. After placing the Top view, I created a Section view and the Section view took over letter A and the Top view (the first view placed) took over letter B. I went a step further and created a Section view of Section A-A. NX made the second section B and the Top view then took over letter C.

I assume the same will happen with other "detail" types of views like Details, Broken, etc.

Maybe this info will help others a little.

Tim Flater
Senior Designer
Enkei America, Inc.

http://www.enkei.com

Some people are like slinkies....they don't really have a purpose, but they still bring a smile to your face when you push them down the stairs.