sheet number 2

[vitulaaak]

I would like to create a followig note on my drawing:

sheet x of y

i would like x to be the number of current sheet and y the total number of sheets. Is there a way to create such annotation?

 

[JohnRBaker]

For NX 5, we have added the following 'automatic text' items:

Number of the current sheet: <W@$SH_SHEET_NUMBER>

Total number of sheets: <W@$SH_NUMBER_OF_SHEETS>

Numerator of the sheet scale: <W@$SH_SHEET_SCALE_NUMERATOR>

Denominator of the sheet scale: <W@$SH_SHEET_SCALE_DENOMINATOR>

Size of the current sheet: <W@$SH_SHEET_SIZE>

Units of the current sheet: <W@$SH_SHEET_UNITS>

Projection angle of the current sheet: <W@$SH_SHEET_PROJECTION_ANGLE>

Master Model drawing sheet part name: <W@$SH_MASTER_PART_NAME>

Sheet part name: <W@$SH_PART_NAME>

Note that we may add additional items in the future.


John R. Baker, P.E.
Product 'Evangelist'
UGS NX Product Line
SIEMENS PLM Software
Cypress, CA

http://www.siemens.com/ugs

http://www.plmworld.org/museum/

 

[vitulaaak]

Thanks.
Do you also have a solution for NX 3 and NX4 ?
Vita

 

[looslib]

Use part parameters from a program, so they all update properly.

"Wildfires are dangerous, hard to control, and economically catastrophic."

Ben Loosli

 

[Shadowspawn]

Once upon a time... long, long, ago... I wrote a grip that would add 1-100 dwg sheets do a dwg file. The particular note you're refering was added 'on the fly' as a normal note and as the sheets were added. There were no attributes involved either, but the routine did find the total number of existing sheets and add new ones accordingly....

Anyway, I'm wondering if your looking for something to add a note to each existing sheet, auto update the sheet number & total sheets when adding new sheets, or something else (like just adding a note outside the dwg title area for manufacturing types to readily see...).

My grip may be able to be addapted to what you need... reply if interested.

Regards,
SS
CAD should pay for itself, shouldn't it?

 

[vitulaaak]

I would probably be able to write a macro to do that. But I d rather have it as an annotation. The problem with the macro is, that you would have to run it everytime. Unless you could run it automaticaly...

 

[MBrookey]

What I normally do is use part attributes in my detail file. In my case I use the same template detail file that I have created with 20 sht's in it. I have an attribute set up for total # of sht's. All you have to do is make the text in your title block look to a part atttibute. So when you change the attibute it will change the note. I'm not sure if this will help, but I thought it might..

 

[BEAEROHEAD]

Will this work for NX2? If not any ideas?

 

[JohnRBaker]

Setting up an attribute linked to a note on the face of the drawing, where if you manually update the attribute, the note updates, YES, that can be done with NX 2. However, the fully automatic scheme with the speical 'smart text' was not introduced until NX 5.


John R. Baker, P.E.
Product 'Evangelist'
NX Design
Siemens PLM Software Inc.
Cypress, CA

http://www.siemens.com/plm

http://www.plmworld.org/museum/

 

[hudson888]

Have a look at using drawing templates as well. You'll find samples are shipped with UG that do much of what you will need. They work from palettes which are created as .pax files, so if you search the installation directories for those then you'll easily find the appropriately named files and you should be able to follow on from there. A great deal of the time and effort involved with setting up and customizing your drawing formats can be saved by simply adapting these samples.

Best Regards

Hudson