Sketch preferences 2

[cubalibre000]

Hi,
annotation preferences in sketch task are settable also via customer default or only via template ?
For example, exist a preference in customer default to set the placement option of annotation in sketch ?
This question is for setting legacy part file, to avoid set this value on each open.

Thank you...

Using NX 8 and TC8.3

 

[Xwheelguy]

Depending upon the version from which this legacy part file comes, you may have to go into Drafting, set the Annotation default how you like it then save the part file and go back to Sketcher for the setting to take effect....possibly have to close and reopen the file, I cannot recall.

Basically, the Drafting settings USED to control the dimension placement options for Sketcher.

Tim Flater
NX Designer
NX 7.5.4.4 MP2
WinXP Pro x64 SP2
Intel Xeon 2.53 GHz 6GB RAM
NVIDIA Quadro 4000 2GB

 

[cubalibre000]

Sorry, but I'm talking about sketch annotation preferences in modeling environment, not drafting environment.

Thank you...

Using NX 8 and TC8.3

 

[MickyV007]

Yeah but you need to change this setting in drafting application. In modeling goto preferences, you will see that the Annotation field is greyed out.... then goto drafting and do the same, now you can change the Annotation preferences.

Best regards,

Michaël.

NX7.5.4.4 + TC Unified 8.3
Win 7 64 bit (Intel(R) Xeon(R) CPU X5650 @2.67GHz)
24.0 GB
NVIDIA Quadro 4000 + NVIDIA Tesla C2050

 

[Toost]

Cuba, read Tim's reply again.
I don't know if NX8 has added separate Sketch annotation preferences, If not it is the drafting preferences that control how the sketcher looks.

Regards,
Tomas

 

[cubalibre000]

Ok...but I'm talking about preferences setting via customer default.
I don't want edit template or edit each part loaded.

Thank you...

Using NX 8 and TC8.3

 

[JohnRBaker]

We have actually COMBINED the Sketch and Dimension prefernces.

While inside the Sketch Task you have access to Annotation Preferences. If you make a change there and then leave Sketching and go to Drafting and reopen the Annotation Preferences you will find that the changes you made while in the Sketch Task are still in effect. And the same would be true going in the other direction.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA

http://www.siemens.com/plm

UG/NX Museum:

http://www.plmworld.org/p/cm/ld/fid=209

To an Engineer, the glass is twice as big as it needs to be.

 

[Xwheelguy]

Cuba,

Customer defaults DO NOT work for legacy or already existing files, which was what your question indicated. Now that I've read your signature (seeing you're using NX8, my previous response is moot - I was thinking you were using an older version of NX in which case my response would have been appropriate).

Expanding upon John Baker's reply, if you make a change to the Annotation settings in Customer Defaults, then all NEW files will inherit that change. It will NOT affect legacy files (files that exist on disk).

With that said, if you follow John's response and open the legacy file in question and change the Annotation setting in Sketcher, it will change the settings in Drafting and vice-versa. Basically, what you get in Sketcher is what you will get in Drafting for that single file, once it's saved, from that point forward. It will NOT affect existing Sketch dimensions - you will have to do that like changing colors, etc. through the Style menu.

Hope this isn't too confusing.

Tim Flater
NX Designer
NX 7.5.4.4 MP2
WinXP Pro x64 SP2
Intel Xeon 2.53 GHz 6GB RAM
NVIDIA Quadro 4000 2GB

 

[cubalibre000]

Hi,
thank you to all and sorry for the delay.
Before to write here and create some topics, I test.
Then I tested the setting for annotation in customer default, but doesn't work.
The setting in customer default works only if you use blank template.

There are setting that work for legacy parts, for example edit with rollback.
The template can have a setting, but if the customer default have the opposite, each new or old parts have the customer default setting.

Another question is :
Which customer default options set each new or old parts and which setting don't ?

Thank you...

Using NX 8 and TC8.3

 

[cowski]

What the customer default will affect depends on its scope. There are 2 values for scope:[ul][li]Session: the setting will be used on any parts you work on in your 'session' of NX. An example of this is the "edit with rollback on double click" setting.[/li][li]Part: the setting is saved with the part; each part you work with may have its own unique value. An example would be the modeling distance tolerance; if you need to change the modeling tolerance for some reason, you probably don't want to apply it to every part you work on and you certainly don't want it to change depending on what computer opens the file.[/li][/ul]

The session settings largely deal with how you interact with NX (what to do on a double click, where to put a menu, how many errors to report during update, etc). The part settings mostly deal with values and settings specific to each individual part. To see which settings are session/part specific, use the search icon (the binoculars) and enter keyword(s) regarding the setting of interest; the 'scope' column in the results will tell you if it is session or part specific.

http://www.nxjournaling.com

 

[cubalibre000]

Hi cowski,
I give you a star because your post is very instructive for me.
How to discover the scope of the setting, I didn't know.

Thank you...

Using NX 8 and TC8.3

 

[cubalibre000]

Then, when the scope is 'part', only 'blank' template inherit customer default setting.
If I want 'part' scope setting, I need to change the template.

Thank you...

Using NX 8 and TC8.3

 

[JohnRBaker]

As cowski explained you can discover the 'scope' of your Customer Default settings by doing a listing and looking at the column titled 'Scope' to see if the setting will be in effect for a session or whether it will only effect new parts being created. To see all of the settings and their scope, when you open the Customer Default dialog click on the 'binoculars' in the upper-right corner and type in 'all' and you will get a complete listing of every Customer Default item. Now scroll to the extreme right end of the listing and you will discover the 'Scope' column. Just select the column and you will have a sorted list showing first all the 'Part' setting and then all the 'Session' settings.

By doing this list all, there is another thing that you can do which might prove helpful. With each new release of NX, often including MR's, new Customer Defaults items have been added or an existing one has been modified. So if you do a list 'all' you will also find a column titled 'Version Modified' which indicates when this item was either added or last modified. This handy see what new items that I may wish to look at since they're generally related to any changes or enhancements made to NX and here'e a handy list, if you sort it, showing all the changes per version. Just look at the ones for the version/MR you just installed and this can help you better identify what settings that you may wish to check out to see if you might wish to change them or not.

Speaking of changing a setting, there is also a column titled 'Modified' which will show the date that YOU last modified a setting for a particular item. Again this can help when you're considering making more changes or wondering which items are not currently in their out-of-the-box settings. True, the 'Modified' column won't tell you exactly what you changed, but at least you'll know which settings have at least been modified at one time. And if you cross-reference this with the 'Version Modified' you can see that perhaps you changed something a couple of years ago and now you see that latest version/MR has modified that item, now you know that perhaps you should check this one out since there may be a new option added or changed that you may wish to investigate.

Anyway, using the listing tool in Customer Defaults can be very handy at times.

BTW, a quick question: Are any of the Eng-Tips regulars planning to attend the Siemens PLM Connection next week in Las Vegas? If so, please introduce yourself to me if we've haven't already met as I'd like to put a face to the 'handle' ;-)

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA

http://www.siemens.com/plm

UG/NX Museum:

http://www.plmworld.org/p/cm/ld/fid=209

To an Engineer, the glass is twice as big as it needs to be.