Weldment Cut list for selected bodies

[pllmoreau]

Hello,

I do large weldment parts with multiple weldment cuts and I have a cut list at the beginning with all the bodies, then I do the drafting for individual parts in later pages, would it be possible to insert a cut list for a view on the current page that will only have the bodies that are in that view that I chose with ''select bodies'' inside? I tried selecting the view before asking a cut list but it kept bringing the whole cut list.

thank you!

 

[moon161]

Can you hide the unused rows after ballooning the items you have in the view?

 

[Jboggs]

The only way I have found to have a bill of material or a cut list on more than one page is to fake it, and I DO NOT LIKE to do that. Leads to too many errors.
On the other hand, in all but the most unusual cases I have found that fact to not be a problem. All sheets are still part of the same drawing. Item 12 is item 12 no matter which page it appears on.

 

[pllmoreau]

To answer both solutions: I could try hiding the rows, I often have cut lists of 80 parts or more so it may become a heavy task. As for faking it, I would guess it mean making my own table and filling it manually like you said there is a big risk of error and yes like you said the item 12 is still the item 12 but often when changes are made a part can change number so if I don't remember to go change the number on every page it can lead to a lot of mistakes.

I appreciate you guys answering! I will keep looking

 

[SBaugh]

Why not just make configurations?

Scott Baugh, CSWP
Mechanical Engineer
Ciholas

https://www.ciholas.com/

"If it's not broke, Don't fix it!"

faq731-376

 

[jassco]

Hi, Jboggs:

No. You don't need to fake anything. You just need to do according to design intents. You can create as many BOMs or Cutlist as you want via configurations. You can also split BOMs or Cutlist across multiple sheets if they are too long.

Best regards,

Alex

 

[pllmoreau]

Jassco,

I think what Jboggs ment for my application to generate another cut list with only selected bodies from a view instead of the overall cut list splitted into multiple pages. So for exemple I have a whole structure to draft my first cut list will have all the beams and plates, then on another page I will take that structure, use select bodies and go pick out a beam and the plates connected to it to put the dimesnions for it. What I would like to do that I don't know how is on that page generate the cut list for only that beam and it's plates.

 

[jassco]

Cut lists do not exist for parts or bodies. In another word, they are not attributes of the parts and bodies. They only exist for configurations. If you want to have cut lists for certain number of bodies, you need to make a configuration for your selection.

Best regards,

Alex

 

[Jboggs]

My problem with using configurations is that a body in one configuration has a different number in a different configuration. A plate that is item 12 in one configuration can be item 5 in a different configuration. That means the same body will be labeled as different numbers on different sheets. Yes there are ways around that but it confuses the downstream drawing users that aren't Solidworks experts.

 

[jassco]

Hi, Jboggs:

The issue you described does not exist if you make true models. Different configurations in one or multiple parts can have identical bodies.

Best regards,

Alex

 

[pllmoreau]

Jassco and Jboggs

I have not worked a lot with configurations and I don't know if you two are saying the same thing but if I work from the same part, I have a configuration with all my bodies and another configuration with some of those bodies, will the same body in the two configarations have the same item number?

And Jassco what did you mean by true model?

Thank you again!

 

[jassco]

Yes, of course. The same body should have the identical item number.

True model means that you do what you say. You don't do "faking" model(s).

If you have two identical parts but you assign two different part no. (or body number), than you don't do what you say!

Best regards,

Alex

 

[Jboggs]

jassco - I appreciate your point, but I have had "true" models in which the number of bodies in each configuration varies. Depending on how SW chooses to arrange those bodies in the cutlist, one body may end up with different numbers in different configurations. For some simple models you can be careful about how you structure the feature tree to some benefit, but there's no way around this situation in some cases. At least in my experience...

 

[jassco]

It has nothing to do with how SW chooses to arrange those bodies in the cutlist. It is all up to you. You have full control on design intent.

Can you share images of your configurations and cutlists?

Best regards,

Alex

 

[pllmoreau]

Hello Jassco,

was your last question directed at me or Jboggs?

 

[Jboggs]

pllmoreau - Weldments always have at least two configurations: "As Welded" and "As Machined". Since machining will not remove any bodies, normally both configurations will have the same number.

The problems I have seen is when I try to create other configurations in which some bodies are intentionally omitted.

 

[SBaugh]

Back to your original question. I tried this out and I cannot get it to give me a table of just the selected bodies even using configurations because all it does is hide the bodies not suppress them. If you could suppress the bodies and only keep the ones you want then it would be possible.

You could put the Weldment cutlist on the first page ballooned, then on the second page put the same weldment cutlist, but drag it off the page and hide the table. Then you can balloon the bodies and it will follow your cutlist and the person reading it will think it's coming from the first page.

I am using SW 2023. If you want to see my simple sample let me know and I will attach it to this post.

Scott Baugh, CSWP
Mechanical Engineer
Ciholas

https://www.ciholas.com/

"If it's not broke, Don't fix it!"

faq731-376

 

[jassco]

Hi, pllmoreau:

This statement below does not make sense to me.

"...would it be possible to insert a cut list for a view on the current page that will only have the bodies that are in that view that I chose with ''select bodies'' inside?"

Do you have an example to show what you are trying to achieve?

Happy New Year!

Alex

 

[SBaugh]

jassco: There is an option "select Bodies" when putting a weldment into a drawing. It will only show you those bodies that you selected. You can see that in my image above. He wants a weldment cutlist to only show those selected bodies and not list all the bodies in the weldment.

Scott Baugh, CSWP
Mechanical Engineer
Ciholas

https://www.ciholas.com/

"If it's not broke, Don't fix it!"

faq731-376

 

[jassco]

Hi, SBaugh:

A weldment is nothing more than a multiple body part.

Let's say the OP wants to a multiple body part made of body A, B, C, D, E and F.

If he wants to show a cut list for A, B, and C, he just needs to make a configuration for A, B, and C.

If he wants to show a cut list for D, E, and F, he just needs to make another configuration for D, E, and F.

Best regards,

Alex