WAVE Linker

[UGMENTALCASE]

Hi all,

We are currently working to standards laid out by our customer, and we have to use an environment, which has been set up, which includes seed files, drawing borders etc etc.

My question is, we are not allowed to use WAVE Linker, once upon a time we had an assembly you make the part workable and then link in using WAVE linker a surface/curve or whatever it was. However since we are not allowed to use it, is there a way around bringin in surfaces from one part to another. Nothing is on the same axis so that doesn't help. The set up we work in seems to block anything to do with the WAVE linker. Even if i save my parts in this environment, and then open the part in a standard NX 6 session, i still can't use WAVE linker, it seems to completely block any use of it, even after a file save.

Any help would be great!

 

[jerry1423]

You can use "promotions" but that only deals with solid bodies.
Inset -> associative copy -> promote
What you do is bring the part in the file as a component and then "promote" it.
From there you can extract the faces, and do what you need with them.
"Promote" needs to be toggled on in your customer defaults.

Maybe what you can do is extract the faces in the original body, than have a reference set with only those faces (surfaces)in it, and bring that into the as a component, and "promote" it if you need to.

 

[JohnRBaker]

Are you not allowed to USE the WAVE linker or is it that once you deliver files back to your customer there can be NO WAVE linked objects in them? If its the latter case, then simply create the WAVE links during your working sessions, do you thing and then premanently break the links before you're ready to deliver the files.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA

http://www.siemens.com/plm

UG/NX Museum:

http://www.plmworld.org/p/cm/ld/fid=209

To an Engineer, the glass is twice as big as it needs to be.

 

[UGMENTALCASE]

Cheers I'll try the promote option now. No it's a complete and utter no go area, to use them. This environment blocks the use of WAVE linking so you couldn't do it if you wanted to!

 

[UGMENTALCASE]

Looks like promote doesn't work. Get the following error:

Promotions are currently disabled in your customer defaults.

 

[JohnRBaker]

The next time you're having a conversation with your customer, ask him if he drives home at night using only low gear or if he watches TV with the speakers permanently muted? It would seem to make about as much sense.

John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA

http://www.siemens.com/plm

UG/NX Museum:

http://www.plmworld.org/p/cm/ld/fid=209

To an Engineer, the glass is twice as big as it needs to be.

 

[UGMENTALCASE]

Tell me about it! They are a bush of twats! I've tried alsorts, we had about three ways of doing things, and none of them work as they have all been blocked. Unless they have some super hidden special way where by you have to shell out for stupid licenses or something.... I don't know they make me angry, and they wonder why everything takes so long!

 

[UGMENTALCASE]

Just tried the work around to turn on the settings and they are all locked. It's even set up so that every part you open doesn't fully load, you have to go and change assembly load options from search folders to from folder, and then load everything, everytime you open something!!!!!!! What's the point in that?!?!?!?!?!

 

[cowski]

I worked in a company where wave links were technically allowed, but highly discouraged. Passing geometry between parts is still possible, just much more difficult.

If you want to get geometry from a component to the assembly, make sure the WCS of the assembly and component are in the same position, then use File -> Export -> Part... to export the geometry you want. I would advise using the 'remove internal parameters' if you can, otherwise you may pull in a lot of unwanted parent geometry.

http://www.nxjournaling.com

 

[UGMENTALCASE]

I thought that one might come up. To be honest yes I can do that but these are aircraft parts and have axis systems in bonkers places! So I have two parts (that make up an assembly pair) that are equal in overall sizes however the surface cuts are all different. So doing it that way I'll have 20 parts all with different set ups and that's just a bit too much time. But I appreciate the thought.

 

[UGMENTALCASE]

We have found a way! Strangely it's as simple as a copy and paste!

In the assembly, mark your work part active. Drift over the part you want to copy until your curser changes, right click select from list. Pick the bit you want to copy, then go edit, paste special, select the axis system you want to paste it relative to, and hey presto!

 

[cowski]

<slaps forehead>
I used that a lot as well, I should have remembered it. I guess the pain of the other method made a bigger impression.

http://www.nxjournaling.com

 

[UGMENTALCASE]

Well it's all a bit bizarre ain't it? They put a stop on a linked body/ surface or whatever and yet you can just copy and paste any old shit into your part?!?!?! Doesn't make sense to me that! Anyway that's how you do it, although you need to make sure your part your copying the bits from is in reference set MODEL, as I first did it got all excited and then it wouldn't do it again. One hour later I figured it by changing reference sets!